Re: [Paparazzi-devel] MicroStrain IMU

[antoine . drouin]

Hi Mohammad

why don't you want to use the makefile to generate your gerbers ? manual
processes are error prone and hardly reproductible. Anyway, if you absolutely
want to do it that way, the makefile will tell you which layers to select


from hw/Makefile


# Component side
%.cmp : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< Top Pads Vias
# Solder side
%.sol : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< Bottom Pads Vias
# Solder stop mask comp. side
%.stc : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< tStop
# Solder stop mask sold. side
%.sts : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< bStop
# Silkscreen comp. side
%.plc : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< Dimension tPlace tDocu
# Drill data for NC drill st.
# warning : eagle takes path of -R option from input file directory.
%.xln : %.brd
        eagle -X -N -d EXCELLON -E -0.02 -E 0.1 -R fab/eurocircuits.drl -o $@ 
$< Drills
Holes
# Outline
%.bor : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< Dimension
# Inner layer top
%.l02 : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< Route2 Pads Vias
# Inner layer bot
%.l15 : %.brd
        eagle -X -N -d GERBER_RS274X -o $@ $< Route15 Pads Vias


hth

Poine


Quoting Mohammad Ali Haji Pour <address@hidden>:

> Dear all,
>
> Can anyone tell me which layers to select to tag in the cam process every
> time to generate all 4 layers ? For example, when selecting Route15 what else
> should I select ?
>
> Regards,
>
> Mohammad
>
>
> _______________________________________________
> Paparazzi-devel mailing list
> address@hidden
> http://lists.nongnu.org/mailman/listinfo/paparazzi-devel
>